Boss

 

 

 

This command allows  a boss having the same shape as the profile used to be created on a part.

 

Creation Stages / Use:

 

Click the icon or select Shape > Boss... from the drop-down menu.

 

  1. Select the shape to modify.

  2. Select the section to use for generating the boss.

  3. Define, if need be, the elevation direction of the boss (normal to the section by default)

  4. Define the limit of the vertex of the boss (see the available options for the different available modes).

 

 

If the profile is open, you should Thicken it to use this command.

 

 

  • Click the yellow handles to rapidly and dynamically modify the height and draft of the boss.

  • Double click the labels to enter the heights and draft values.

  • To create a new sketch "on the fly", click the "+".

 

 

Available Options:

 

 

You can define the limit of the boss in several ways:

  • Height: enter the value for the height of the boss, measured in relation to the section.

  • Point: define a point for the bound of the bottom of the pocket.

  • Plane: select a trimming plane for the vertex of the boss.

  • Surface: select a surface (plane or curve) in order to trim the vertex of the boss.

  • Face set: select a face of the shape in order to trim the elevation on this face and all of the faces adjacent to it.

  • Shape: Select a shape against which the boss must be trimmed

  • Through: the boss rises up to the first face of the shape that completely intersects the section of the boss.

  • Through all: the boss rises up to the last face of the shape that completely intersects the section of the boss.

  • Through all in both directions: the boss rises on both sides of the section up to the last face of the shape that completely intersects the section of the boss.

  • In place: The section defines the vertex of the boss.

 

 

By checking this box, you will be able to add a draft on all lateral faces of the boss.

 

 

For limits like Point, Plane, Surface, Face set, Shape, it is possible to add an offset.

 

Example of an offset limit regarding the surface.

 

 

This option allows you to extend the boss in the opposite direction of the rising of the boss. This option is useful for example when the section of the boss is not in contact with the start face but is located slightly above.

 

 

 

Blend: Blend: Allows you to add a fillet or a chamfer at the base of the boss.

  • None: There is no blend.

  • Chamfer: Enter the value for the two lengths of the chamfer.

  • Fillet: Enter the value of the radius. The "rounded corners" checkbox allows you to obtain a rounded connection between the fillets arriving at a sharp angle.

  

Fillet blend without rounded corners

Fillet blend with rounded corners

 

Fillets: Allows you to add fillets.

  • Upper radius: on the edges of the vertex of the boss.

  • Vertical radius: on the lateral edges of the boss.

 

 

 

This option allows to create the boss regarding another plane face of the part. This face must be parallel to the sketch plane.

The boss height is calculated regarding the reference plane and not the sketch. In the example below, the Extend option must be checked

 

Sketch

 

Pocket

 

Reference plane