Drilling group

This command allows you to carry out several identical drilling operations in one operation. The position and the number of drillings is defined by the points of the a reference sketch.

Creation stages / Use:

Click the icon or select Shape > Other operations > Drilling group... command from the drop-down menu.

The first stage of this function is identical to the Drilling function and allows you to select and/or define a drilling template.
Select the sketch containing the position points of the drillings.
Select the mode :

Allows you to drill sketch (not internal) points.

Allows you to drill sketch circles. If this mode is activated, there are 2 possibilities:

If all circles have the same diameter, TopSolid uses the measured value of the circle diameter as hole diameter.
If circles have different diameters, TopSolid uses the default values for each kind of hole.

Allows you to drill sketch points and circles.

Define the direction of the drilling.
Select the shape to drill.
Validate the operation with .

To be able to create tapped holes, you need to reference a library containing the standard you wish to use for the tapping.
To unselect one of the 2 modes, just click again on the corresponding icon.
At least on of these modes has to be selected.
This operation is compatible with the Create MF option (available from de Home tab).

Advanced Options:

Machining process:

Available Options:

Templates and types of drilling:

Sketch:

Select the sketch here to use for defining the position of the drilling.

The drillings are created in all the points with the status non-internal in the sketch.

In other words, if no point of the sketch is visible outside the sketch's editing mode, then no drilling can be created.

All the points used must intersect the shape following the defined direction. If one of the points is "in space" the operation cannot be run.

Direction:

Define the direction of the drilling.

The defined direction represents the Z+ of the drilling frame. However, the drilling is done based on Z-

Therefore, take care to note the direction indicated by the arrow which must indicate the opposite direction of the drilling (towards the exterior of the material).

Shape to drill:

Select the shape on which the drillings will be done.

Grouped drilling can only be done on one shape. Several shapes cannot be selected on the same operation.

Pattern:

Possibility to select a reference point corresponding to the pattern origin. This origin and the drilling group repetition will be automatically proposed in an assembly using this part to repeat a component with the same pattern.

If in the assembly, a component is positioned at this place and if it is repeated, by flying over the drilling group, you will have access to the pattern defined by the drilling group. Without this reference point, the drilling group pattern will not be proposed when repeating the component in the assembly.

Drilling processes:

Below the main options, a list of icons is displayed which allows you to modify the parameters of the different procedures of the drilling template used.

By default, the values are those of the drilling template. It is therefore not required to access this if the values of the template are those you wish to use.

See here for the detailed description of the different procedures.