Draft

This command allows you to create drafts on the faces of a shape.

Creation Stages / Use:

Click the icon or select Shape > Draft... from the drop-down menu.

Enter the draft angle.
Choose the creation mode of the draft.

	With the reference plane
	With the parting line
	On isoclines
	With step

Depending on the chosen creation mode, you must define:

- either the reference plane and faces to draft.
- either the reference direction and edges of the parting line.
- or the draft direction and faces to draft.

Available Options:

Draft in Reference Plane Mode:

Plane: this option allows you to define in relation to which plane the draft is applied. The blue arrow indicates the reference direction of the angle.

Face: this option allows you to define on which faces the draft is applied.

Draft in Parting Line Mode:

Direction: This is the reference direction for the measurement of the draft angle. In other words, this can represent the mold opening direction of the part.

Parting lines: add to this list the edges around which the faces will "pivot" in order to generate the draft.

By clicking the small icon in the "invert" column, the face of the other side of the edge will be treated.

Draft on isoclines mode:

With this mode, fillets are between the fixed face (indicating the direction) and faces to draft are to be selected.

Direction: This is the reference direction for the measurement of the draft angle. In other words, this can represent the mold opening direction of the part.

Faces: Select faces to which the draft is applied.


Initial part	In blue: the direction, in pink : selected faces, in transparent orange: the preview

Rebuild blends: This option has to be checked if faces to draft have fillets.

Draft with step:

This mode allows you to apply draft on faces with a step following edges. the drafted face will not be divided according to the reference edges, but a step will appear on the edges.

Faces: Select faces to which the draft is applied.

Step edges: Select all the fix edges of the face.


Tapered step (surfaces are generated the same way as the face to draft)	Normal step (surfaces are ruled surfaces perpendicularly to the face to draft)	Step with sheet (surfaces based on the geometry of the parting surface)

Special Faces:

Option specific to the mode

This option allows you to assign specific draft angles for certain faces.

Select the faces in order to add them to the list and to modify the draft angle in the list.

Advanced Options:

Smooth boundary edge: If the drafted faces have smooth lateral edges (tangency with another face), then a lateral face is created to allow the draft to be created.

Smooth edge: In the case of two drafted tangent faces with different angles, this option creates a lateral face at the tangency edge.

Initial shape	Option disabled	Option Enabled

Extend mode: This mode allows to select how the draft should react regarding a close geometry like for example a hole.

Automatic or drafted faces	Fixed faces	None

Additional information: